HEIDENHAIN TNC 426 B User Manual

110
6 Programming: Programming Contours
Example: Circular movements with Cartesian coordinates
6.4 Path Contours — Cartesian Coordinates
Example: Circular movements with Cartesian coordinates
0 BEGIN PGM CIRCULAR MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL DEF 1 L+0 R+10
4 TOOL CALL 1 Z S4000
5 L Z+250 R0 F MAX
6 L X-10 Y-10 R0 F MAX
7 L Z-5 R0 F1000 M3
8 APPR LCT X+5 Y+5 R5 RL F300
9 L X+5 Y+85
10 RND R10 F150
11 L X+30 Y+85
12 CR X+70 Y+95 R+30 DR-
13 L X+95
14 L X+95 Y+40
15 CT X+40 Y+5
16 L X+5
17 DEP LCT X-20 Y-20 R5 F1000
18 L Z+250 R0 F MAX M2
19 END PGM CIRCULAR MM
Define blank form for graphic workpiece simulation
Define tool in the program
Call tool in the spindle axis and with the spindle speed S
Retract tool in the spindle axis at rapid traverse FMAX
Pre-position the tool
Move to working depth at feed rate F = 1000 mm/min
Approach the contour at point 1 on a circular arc with
tangential connection
Point 2: first straight line for corner 2
Insert radius with R = 10 mm, feed rate: 150 mm/min
Move to point 3: Starting point of the arc with CR
Move to point 4: End point of the arc with CR, radius 30 mm
Move to point 5
Move to point 6
Move to point 7: End point of the arc, radius with tangential
connection to point 6, TNC automatically calculates the radius
Move to last contour point 1
Depart the contour on a circular arc with tangential connection
Retract in the tool axis, end program
X
Y
95
5
95
5
85
40
4030 70
R10
R30
Gkap6.pm6 30.06.2006, 07:04110
www.EngineeringBooksPdf.com

HEIDENHAIN TNC 426 B Specifications

General

Brand	HEIDENHAIN
Model	TNC 426 B
Category	Control Systems
Language	English