HEIDENHAIN TNC 426 B User Manual

8 Programming: Cycles
164
RIGID TAPPING (Cycle 17)
Machine and control must be specially prepared by the
machine tool builder to enable rigid tapping.
The TNC cuts the thread without a floating tap holder in one or
more passes.
Rigid tapping offers the following advantages over tapping with a
floating tap holder
■
Higher machining speeds possible
■
Repeated tapping of the same thread is possible; repetitions are
enabled via spindle orientation to the 0° position during cycle call
(depending on machine parameter 7160).
■
Increased traverse range of the spindle axis due to absence of a
floating tap holder.
Before programming, note the following:
Program a positioning block for the starting point (hole
center) in the working plane with radius compensation R0.
Program a positioning block for the starting point in the
tool axis (set-up clearance above the workpiece surface).
The algebraic sign for the parameter total hole depth
determines the working direction.
The TNC calculates the feed rate from the spindle speed.
If the spindle speed override is used during tapping, the
feed rate is automatically adjusted.
The feed-rate override knob is disabled.
At the end of the cycle the spindle comes to a stop.
Before the next operation, restart the spindle with M3
(or M4).
ú
Setup clearance (incremental value): Distance
between tool tip (at starting position) and workpiece
surface
ú Total hole depth (incremental value): Distance
between workpiece surface (beginning of thread) and
end of thread
ú
PITCH :
Pitch of the thread. The algebraic sign differentiates
between right-hand and left-hand threads:
+ = right-hand thread
– = left-hand thread
8.2 Drilling Cycles
X
Z
Retracting after a program interruption
If you interrupt program run during tapping with the
machine stop button, the TNC will display the soft
key MANUAL OPERATION. If you press the MANU-
AL OPERATION key, you can retract the tool under
program control. Simply press the positive axis
direction button of the active tool axis.
Example NC blocks:
18 CYCL DEF 17.0 RIGID TAPPING GS
19 CYCL DEF 17.1 SET UP 2
20 CYCL DEF 17.2 DEPTH -20
21 CYCL DEF 17.3 PITCH +1
kkap8.pm6 30.06.2006, 07:03164
www.EngineeringBooksPdf.com

HEIDENHAIN TNC 426 B Specifications

General

Brand	HEIDENHAIN
Model	TNC 426 B
Category	Control Systems
Language	English